So, I don’t usually have to deal with threads and I don’t normally use the hole wizard (I just model my holes, novel).
Anywho…what is the preferred method if you want to use this? I have a bearing carrier with a 6 hole bolt pattern that I want to place as a feature. I recall something with using points in sketches and doing it that way, and then adding holes to the points, but I couldn’t quite work it out myself nor find the previous threads on the old forum.
Any takers?
Hole Wizard is VERY easy to use and to get right. Just pick the hole you want, for instance an M6 threaded thru hole, and then you have a tab for Positions. It sounds like that is what you missed. Positions automatically selects the Point icon so you just put the points where you want the holes. Toggle that Point icon off and then dimension the points or constrain them the way you want to control them and presto you have your holes.
Besides automatically sizing the holes and doing the sketches for us, one of the best things about the Hole Wizard is that these will populate the drawing with the proper hole callout and number of instances. IMHO, if you aren’t using Hole Wizard you are making your CAD life more difficult than it has to be.
The Hole Wizard has a lot of benefits when it comes to making drawings, patterns, mating toolbox parts, and other stuff. Avoid making detailed threads, and use the cosmetic thread option. This will help with performance, and simplify your drawings. No one needs to see the thread geometry unless you are 3D printing your part, or making something very non-standard.
If you start the Hole Wizard with a plane selected, your hole center points will all be in a 2D plane. If you start it without a plane selected, your points go into a 3D sketch, which allows you to have hole centers on multiple levels, but it also complicates sketching a lot.
Besides automatically sizing the holes and doing the sketches for us, one of the best things about the Hole Wizard is that these will populate the drawing with the proper hole callout and number of instances.
This is the primary reason I DON’T normally use the hole wizard. I have no need of this aspect and seem to call out my holes just fine. I haven’t used it in awhile, but I actually found previous callouts to be formatted differently than our standards and too cumbersome to edit. It was easier to just use regular dimensioning.
So, just to clarify, I’m supposed to place the holes and THEN dimension/constrain the points?
It’s a wizard, let it walk you through. Specify Type, then specify Positions. Use the tabs.
Oh, I got that 3D sketch thing screwed up. It seems they fixed that. You get a 2D sketch unless you hit the 3D sketch button on the Positions tab.
3D sketches allow holes on different levels and in different directions.
image.png
I use the Hole Wizard extensively for drilled holes and slots, though not so much for threads. My preferred method, that I’ve used for many years, is to create a stand-alone sketch first, then when I get to the hole wizard feature I just drop the points coincident with end points, mid points, etc from my driving sketch. It only takes a few seconds.
Using the Hole Wizard has multiple benefits, such as inserting and mating one set of hardware, then using the Hole Wizard feature to drive a Pattern Driven Component Pattern to place the rest. Another benefit is using a Hole Callout in the Drawing.
You mentioned a 6 hole bolt pattern. Below is a Part I’m working on right now that has several hole wizard features. Below is the sketch I used to drive one of them, with the result. By the way, as you can see, I really like using the Center Rectangle sketch tool. I usually make the outside lines construction, but it’s not really necessary.
Another “by the way”; I typically pre-select the face before starting the Hole Wizard feature. That eliminates the issue above that matt brought up. As soon as I go to the second page of the feature manager the point sketch is automatically active.
Here is another example from the same Part.
Or if I’m not mistaken pick a non planar surface. So it automatically puts you into a 3D sketch if you pick a cylinder or some other non planar object.
is to create a stand-alone sketch first, then when I get to the hole wizard feature I just drop the points coincident with end points, mid points, etc from my driving sketch. It only takes a few seconds
So, I tried that, but I think I was adding an additional unnecessary layer and that was what was causing the problem. So, once I create my driving sketch, I can place the holes on the sketch endpoints without creating ADDITIONAL 3D points. I think that’s where I tripped myself up.
Hmm…I guess some of my issue is that trying to polar array sketch points seems…different…
Without Hole Wizard, how do you know a hole on model is just drilled or taped?
Remember all the tape drill size?
You can do circular patterns in the position sketch.
I’m not sure I understand what you’re saying. Just to be clear, my driving sketch is completely independent of the Hole Wizard feature, and shows above it in the tree. The only entities in my Hole Wizard sketch are the sketch points that define the hole locations.
Indeed. But then I still need to constrain the resultant pattern, so…seems less useful since I want points and those points get generated by sketch geometry needed to constrain those points. Unless I’m doing something terribly wrong (which is possible).
And, it seemed slightly more flaky than the feature patterning (of course, it’s probably me that’s flaky).
@Frederick_Law - So, I guess I’m too used to being a one man band. That’s a good consideration. It’s weird. It’s possible I’m misremembering, but when I first started using SW again in 2018 I remember reading a lot of consternation about the hole wizard and whether it was worth using or not. Maybe that whole idea is a moot point at this time.
Sure you’re not thinking about the ToolBox rather than the hole wizard? I don’t know of too many people not using the Hole Wizard but there’s quite the disagreement about whether to use the Tool Box or not.
My thinking is along the same lines as MJuric…
should I be concerned?..need to check my temperature…maybe I’m not over covid?
The Hole Wiz is the thing that makes Toolbox almost worth using. When it works according to “the vision”, it’s a beautiful thing. But you have to check a lot of boxes before you get to “the vision”.
Welcome to the Dark Side…
To me the hole wizard is a complete no brainer. I can not imagine any other method of placing holes that would come even close. Sure like anything else to get 100% out of it you have to do a little set up, but even out of the box it’s better than any other method.
Toolbox usage will really depend on what you’re using it for, how often and what your needs are.
I use the hole wizard in a similar way to Glenn Schroeder. However, I do not define the hole positions in the wizard but already in the sketch. With the wizard I also insert only one hole. At the top left, at the place with the circle, there is no sketch point for the hole in the sketch. I then use the hole and the sketch with the points to create a sketch pattern.
image.png
It is important to check “Geometry pattern” in the menu of the sketch pattern. This setting has a great influence on the speed…
image.png
For comparison, the performance comparison when the holes are all positioned in the Wizardt
This is true, but it only works where every instance of the hole is exactly the same. It won’t work on multiple level holes, or holes that intersect other features. Geometry Pattern is a great thing to use, but you also have to be ready and know what to do when it fails (basically turn it off).