have a “thickness” variable that gets used in sheet metal parts
name the standard planes the way you want them
part templates for materials I use often, so I have some of the properties already set up
part templates for different units - I usually like to model to 4 places inch, just to make sure that my model is really what I intend it to be
it is recommended to make new templates for each version…
make templates with all the same capitalization on the extensions - makes stuff easier to browse visually if they are all the same (SLDPRT vs sldprt or even sldPRT)
drawing templates with the formats already on them
in each size
using multiple sheets and a special format for the second sheet
format with company logo - multiple if you make drawings for other companies
prefer B size so they are easier to print
use predefined views on drawing templates to pre-populate sheet with views of part/assembly
use anchor points for various tables on the format
-there is no real reason to use XYZ axes since you can use a primary plane for a pattern direction.
-I keep virtually all of our materials in Favorites. It takes two clicks to set it each time…
-units? I agree there. I can’t stand two-place decimals OR eight-place decimals. <()>
-how come “B” is easier to print than say, A3 or A4?
-I don’t use predefined views much because they don’t work with SM flat patterns.
I know I’ve used them for other things, and I just like having them. But, the other day I tried doing a circular pattern, and thought, I’ll just use an axis…you can’t, and I’m not sure why?
Due to Crusty Old Template File Gotcha, I keep the number of templates to a minimum, since they have to be recreated every SW version. A single part and a single assembly template with drafting standards set accordingly (4 place decimal, since I usually design in fractional inches. Image quality set low enough that I don’t run in to TARDIS Parts.
Default planes are named Plane1, Plane2 and Plane3 because for the equipment I design, Front, Top and Right have no meaning.
Four separate standard drawing templates, A,B,C and D. The print settings on the C and D are set to 50% so that they can be printed on 8.5 x 11 and 11x17 paper. A couple of other drawing templates for very specific drawings we create on a regular basis that have a lot of standard tables and blocks that don’t appear on our standard drawings.
I had axes set up in my assembly Template for a number of years, but like @mike miller said, I deleted them when we got the ability to use planes for pattern direction.
I also like 4 place decimals in my Part and Assembly templates, but my Drawing templates are all set to display fractions to the nearest 1/16". I occasionally need to show decimals, but I have Styles saved to override the Units settings for those situations.
Speaking of Styles, I have a number of them saved in my templates. They’re in my Drawing templates for Dimensions, Notes, and weld symbols, and for Hole Wizard slots in my Part template.
Something else I’ve done that isn’t exactly a template issue, I have a Drawing that’s full of notes that I use occasionally, but didn’t want cluttering up my note Styles. I have it pinned, so when I go to Recent Documents it’s always at the top. It’s pretty easy to copy from that drawing and paste in the one I’m working on.
We have a variety of customers, so each customer gets their own sheet formats and templates. When I set up the drawing template, I only make it for the first sheet. I then make sure to set the “Sheet format for new sheets” in the document properties (Drawing Sheets), to be the format for the second sheet for that customer.
If one engineer is the most likely to work on a particular project, I may set their name for “Drawn by” in the template also. It can be changed easily if needed, but if not, it saves a step.
Any reason why? Keeping all version in sync (and asking user to use the right version) seem to be a lot of works…
use predefined views on drawing templates to pre-populate sheet with views of part/assembly
I am not really a big fan of predefined view…
We had it setup but no one is using it and they delete the predefine view most of the time, so we remove them in the end…
One thing that I had noticed about predefined view is that it wont “scale” automatically when you first create the drawing.
I recall posting a question in the old forum last year when i was working on our template but dont think i get any answer https://forum.solidworks.com/thread/239403
